ABSOLUTE COORDINATES (G53)
For rapid linear motion to a point expressed in absolute coordinates, program: G01 G53 X~ Y~ Z~ (or use with G00 instead of G01)
All the axis words are optional, except that at least one must be used. The G00 or G01 is optional if it is in the current motion mode. G53 isn’t modal, and must be programmed on each line on which it is intended to be active. This produces coordinated linear motion to the programmed point. If G01 is active, the speed of motion is the current feed rate (or slower if the mill won’t go that fast). If G00 is active, the speed of motion is the current traverse rate (or slower if the mill won’t go that fast).
It’s an error if:
- G53 is used without G00 or G01 being active
- G53 is used while cutter radius compensation is on